How to Use Hole Wizard in SOLIDWORKS

Hole Wizard is the standard SOLIDWORKS tool for creating common hole types quickly and accurately. Instead of sketching a profile and building every hole manually, you select a hole standard, choose the type and size, define the end condition, and place the hole using the Positions tab. That is why Hole Wizard is usually the best starting point for counterbores, countersinks, tapped holes, and many other production-style hole features.

The main advantage is not just speed. Hole Wizard also keeps hole definitions tied to recognized standards, which helps with fastener fit, drawing callouts, and later edits.

This guide explains how Hole Wizard works, how to use the main settings properly, and what to check when your hole locations or callouts are not behaving the way you expect.

What is Hole Wizard in SOLIDWORKS?

Hole Wizard is a feature-based hole tool that creates standard hole geometry without requiring you to sketch every cross-section manually. It is designed for production hole types such as clearance holes, counterbores, countersinks, straight tapped holes, tapered tapped holes, and several slot-based variations.

In practice, Hole Wizard is useful because it handles two jobs at once:

• it defines the hole specification such as type, standard, size, and depth
• it defines the hole positions on the selected face or sketch points

That split between Type and Positions is the key to understanding the tool.

The basic Hole Wizard workflow

For most parts, the process is straightforward:

1. Select the face where the hole will start.
2. Open Hole Wizard from the Features toolbar or use Insert > Features > Hole > Wizard.
3. On the Type tab, choose the hole type, standard, type, size, and end condition.
4. Switch to the Positions tab.
5. Place the hole points on the selected face and fully define them if needed.
6. Accept the feature.

That sounds simple, but most user confusion comes from not understanding what should be decided on each tab.

The Type tab: choose what kind of hole you are creating

The Type tab controls the geometry and specification of the hole. This is where you decide whether you are building a clearance hole, a counterbore, a countersink, a tapped hole, or another supported variation.

The first group of options is usually interpreted like this:

• Counterbore: recesses the fastener head below the part surface
• Countersink: creates an angled seat for countersunk screws or bolts
• Hole: creates a standard simple or clearance hole

SOLIDWORKS also includes slot-based versions of several hole types, so the same general logic extends beyond simple circular holes.

On this tab, you normally set:

• the hole category
• the standard
• the type
• the size
• the fit or dimensions where applicable
• the end condition such as blind or through all

Standards and type lists are not arbitrary. They come from the Hole Wizard and Toolbox configuration, so the exact options available can depend on how the system is configured.

The Positions tab: define where the holes go

The Positions tab controls placement. This is where many new users make the mistake of thinking they are done once the size and type are correct. In reality, a clean Hole Wizard feature depends just as much on good positioning logic as it does on good hole specifications.

The minimum workflow is to select a face and click approximate hole positions. That works, but the feature is often left underdefined until you edit the sketch and add constraints or dimensions.

A better workflow is usually one of these:

• place the points directly and then fully define the resulting sketch
• create a sketch with points first, then use those points to drive the Hole Wizard placement

SOLIDWORKS also supports more precise point placement behavior than older users sometimes expect. On the Positions tab, the first sketch point and a shaded preview of the hole follow the cursor, and you can use sketch snaps and inference lines to place the point more accurately. If you need to place holes across multiple faces, the 3D Sketch option is the key setting to understand.

This matters because Hole Wizard is not just a hole generator. It is also a sketch-driven placement tool.

Using existing geometry to constrain hole locations

One useful placement method is to constrain hole points to existing geometry. Circular edges can help when you want the new hole to stay concentric with an existing cylindrical feature. Hovering the pointer can reveal center points that make concentric placement easier.

This is especially useful when:

• you are building pipe-port geometry
• you need a threaded feature aligned to an existing bore
• you are placing a hole on a round or revolved component

For repeated production work, separate sketches for each hole type and size can also keep the model easier to manage.

Example: straight tapped hole

Hole Wizard is often the best way to create standard internal threads because it combines the drill definition with thread-related information in one feature. For ordinary metric or inch tapped holes, choose the appropriate tapped-hole type and the correct size and end condition.

If the hole is blind, a bottoming-style tapped hole is often the more appropriate option than a generic through-style definition.

Another reason this workflow matters is drawing documentation. Hole Wizard information is what gives SOLIDWORKS the best basis for creating useful hole callouts in drawings. Those callouts update with the model when the hole definition changes.

Cosmetic threads and callouts

For tapped holes, SOLIDWORKS can add cosmetic thread information rather than requiring fully modeled thread geometry. This is usually the correct choice for standard documentation workflows because it is lighter, clearer, and better aligned with how hole callouts work in drawings.

If your goal is manufacturing communication rather than visual thread geometry, Hole Wizard plus cosmetic thread data is usually the right approach.

That also means Hole Wizard is closely connected to downstream drawing output. Best results for hole callouts generally come from holes created with Hole Wizard rather than improvised cut features. For standard callout behavior in drawings, the hole axis should also be normal to the drawing sheet.

Example: counterbore hole

Use a counterbore when you need the fastener head recessed below the surface. The important decision is not just the nominal hole size, but matching the hole type to the fastener style that will actually be used. A socket-head screw and a hex-head fastener do not use the same head geometry, so the counterbore dimensions can differ.

SOLIDWORKS usually lets you choose the desired fit as close, normal, or loose, and then refine dimensions further if needed.

Best practice: always verify the head fit against the real fastener standard you expect to use. A counterbore is only correct if the fastener seats and tightens properly.

Example: countersink hole

Use a countersink when the fastener head needs to sit flush with the surface. As with counterbores, the fastener standard matters. A countersink angle and diameter must match the screw or bolt head style you intend to use.

This is a good example of why Hole Wizard is stronger than drawing a rough cone and circular cut manually. The wizard keeps the geometry tied to an actual hole definition instead of an improvised approximation.

Example: tapered pipe thread

Tapered pipe threads are used when the thread form itself contributes to sealing. In Hole Wizard, choose the correct standard and tapered pipe tap type, then select the required size and end condition.

Unless you have specific custom data to override, the default thread-related dimensions are often the safest place to start.

This is the kind of workflow where a standards-based tool is especially useful because pipe-thread geometry and naming conventions can become error-prone quickly if you build them manually.

Example: parallel pipe thread

Parallel pipe threads are different because the thread itself does not create the seal in the same way a tapered thread does. That usually means the surrounding geometry matters more. In practical terms, you often need additional preparation such as a counterbore or pilot feature before applying the threaded portion.

That is why this type of hole often works best as a staged workflow:

1. prepare the counterbore and pilot geometry
2. apply the threaded portion with the appropriate standard and size
3. verify both hole depth and threaded depth

In other words, Hole Wizard helps with the thread definition, but the surrounding seal and port geometry still need to make engineering sense.

What about slots in Hole Wizard?

Hole Wizard is not limited to round holes. SOLIDWORKS also supports slot creation through Hole Wizard, including counterbored, countersunk, and straight-slot variants. On the Positions tab, slot orientation can also be adjusted, and SOLIDWORKS documentation notes that the Tab key can rotate the slot by 90 degrees during placement.

This is worth knowing because many users treat slots as a separate modeling problem when Hole Wizard can already handle them in a standards-aware way.

The final result should not just look correct. It should also be driven by the right standard, placement logic, and documentation behavior.

Common mistakes when using Hole Wizard

• Leaving the placement sketch underdefined: approximate clicks are fast, but the model becomes fragile if you never constrain the points properly.
• Choosing the wrong fastener family: counterbores and countersinks depend on the actual fastener type, not just a rough diameter.
• Ignoring the difference between tapered and parallel pipe threads: the surrounding geometry and sealing assumptions are not the same.
• Modeling standard holes manually: this usually creates more work and weaker drawing callout behavior than Hole Wizard.
• Assuming cosmetic thread data is the same as modeled threads: Hole Wizard is usually for documentation-ready thread definitions, not helical thread geometry.
• Changing hole types without reviewing transferred settings: SOLIDWORKS can preserve type-specific settings or transfer them when you switch hole types, which can lead to unexpected size matches.

Best practices

• Use Hole Wizard for standard hole families: it is usually faster and more robust than building them from cuts.
• Fully define the Positions sketch: especially on parts that may be revised later.
• Match the fastener standard first: then trust the wizard dimensions as a starting point.
• Use Hole Wizard data to support drawing callouts: this is one of its biggest advantages.
• Separate different hole types into separate features when it improves clarity: that usually makes edits easier later.
• Save repeatable setups as Favorites when useful: that speeds up recurring hole definitions and reduces setup drift.

FAQ

What is Hole Wizard used for in SOLIDWORKS?

It is used to create standard hole features such as simple holes, counterbores, countersinks, tapped holes, pipe-thread holes, and slot variants without manually sketching all the geometry.

What is the difference between the Type tab and the Positions tab?

The Type tab defines the hole specification. The Positions tab defines where the hole instances are placed on the model.

Can Hole Wizard help with drawing callouts?

Yes. Hole callouts in drawings work best when the hole was created with Hole Wizard because SOLIDWORKS can use the hole-definition information directly.

Should I sketch points first before using Hole Wizard?

Sometimes. For quick holes, direct point placement is fine. For more controlled or repeated layouts, prebuilt sketch points can make the feature easier to constrain and maintain.

Does Hole Wizard create real modeled threads?

Usually no. For tapped holes, it commonly works with cosmetic thread information and hole callout data rather than full helical thread geometry.

Final thoughts

If you use standard holes regularly, Hole Wizard should be one of your default tools in SOLIDWORKS. It is faster than manual cut-based workflows, better for standards-based hole definitions, and much stronger for downstream documentation.

The most important habit is to think of the tool in two parts: define the right hole on the Type tab, then define the right placement on the Positions tab. Once that clicks, Hole Wizard becomes much easier to use well.